The drawing of the X-CHAIN parts, and these instructions, are provided under the CERN Open Hardware Licence Version 2 - Strongly Reciprocal.
See LICENSE.txt .


To prepare drawing X-CHAIN.DXF for cutting on a SheetCNC machine.
-----------------------------------------------------------------

In your CAM program, create the following operations:

Material: MDF, or good quality ply (no voids), 25mm thickness. Red-and-white (WBP) generally has poor glue layers. So prefer MDF or marine ply.

Origin: is 0,0 at bottom-left of drawing.

Units: mm. Approx material size required per pair is 400x250mm.

1) Drill 3mm depth on all points marked in layer FIX-DRILL.
   6mm 1-flute end-mill will suffice for this. It saves a tool-change for the next operation.
   Alternatively drill full-thickness with 3mm twist-drill.

2) Mill, internal offset, H-THRU-STEEP. Full depth of the material (say, 26mm).
   We prefer to cut these in one pass (DOC=26) with a ramp angle appropriate to create a 3mm-per-turn helix.
   6mm 1-flute end-mill is preferred for this.
   
2a) OPTIONAL. Drill, full depth of the material, with a 10.2mm dia drill, points in layer D-LAST-09.9-THRU.
    10mm dia or 10.5mm dia may suffice, if 10.2mm not available.

3) Mill, no offset, E-16.0 . Cut 16mm depth.
   We prefer to cut these forward-and-reverse in one pass (DOC=16) with a ramp angle appropriate to create a 2mm-per-pass cut.
   Such a fine DOC is used because accuracy is very important for these, and they don't take long anyway.
   6mm 1-flute end-mill ESSENTIAL for this.

4) Pocket, no overcutting, P15.0 . Cut 15mm depth.
   We prefer to cut these in three passes (DOC=5), ramped.
   6mm 1-flute end-mill preferred for this.
   
5) Mill, outside offset, OUT-THRU. Full depth of the material.
   We prefer to cut these with DOC 3.25mm (=8 passes) to maximise precision and reduce risk of splitting the plies of the thin parts.
   6mm is maximum possible cutter dia. 6mm 1-flute end-mill preferred.
   Place hold-tabs in two locations on the main body of each part, and another hold-tab at the side of the tip of the spindly protrusion.
   
   
To cut the part on a SheetCNC machine.
--------------------------------------
   
On the SheetCNC machine, load suitable 25mm material, touch-off to bottom-left (as (0,0) ), and run the following operations:

Operation (1). Then fasten the material to the machine bed using 50mm x 3.5mm (or 2" x #6) woodscrews.
Operations (2), (2a OPTIONAL), (3), (4), (5) in that order.

Note: the hold-downs shown in the drawing hold the workpiece but not the finished items. In our experience, provided
the material is MDF and provided the suggested cutters are used, the machined parts will be held sufficiently in
place by tabs and packed cuttings. However, you may wish to add extra hold-downs on the parts themselves, especially
if using aggressive vacuum.


Post-CNC finishing.
-------------------

Remove workpiece from table. Invert it. Cut away the tabs taking care not to split the plies of the parts - they tear easily.
Lay part flat onto the edge of a worktop.
Use a 6mm dia twist-drill in a lightweight electric drill.
Lay the drill bit tip into the bottom of one E-16.0 slot.
Keeping drill horizontal and perpendicular, drill through into the H-THRU-STEEP hole.
Repeat for all slots/holes.
If CNC operation (2a OPTIONAL) was ommited, then carefully use an electric drill to open-out the H-THRU-STEEP holes to 10+mm dia.
